Dynapath Delta 20CNC

Newbie · Feb 8, 2005

Hey does anyone know how to program a Delta 20 CNC. I am trying to get the one at my work to work right. I am using BobCAD to upload the file. Here is a test file that is supposed to start the machine, start the coolant, start the spindle, drill 3 holes with peck drill, stop the spindle, stop the coolant, and end the program. I keep getting a "format error" messege.

(test )
N001G90
N002G80
N003G40
N004G70
N005M08
N006M3S500
N007G04X8.0
N008G83 X3.0709 Y0.9843 Z.25K.125R.125Q.1F2
N009X7.0079
N0010G00 X10.5539 Y0.8996 Z0.
N0011G03 X10.9449 Y0.5842 I0.391 J0.0846F20
N0012Y0.9843 Z-0.025
N0013G80
N0014M05
N0015M09
N0016M02

I would really appreciate some help with this, the Dynapath manual is not very clear on this stuff. Thanks.

ARB · Feb 8, 2005

I am not up on Dynapath but as far a G code goes you have a few suspects.

(test )
N001G90
N002G80
N003G40
N004G70
N005M08
N006M3S500
N007G04X8.0 ( not sure about this one appears to be a dwell command)
N008G83 X3.0709 Y0.9843 Z.25K.125R.125Q.1F2
N009X7.0079
N0010G00 X10.5539 Y0.8996 Z0. (rapid move)
N0011G03 X10.9449 Y0.5842 I0.391 J0.0846F20 (circular move)
N0012Y0.9843 Z-0.025 (???)
N0013G80
N0014M05
N0015M09
N0016M02

I would try ditching the odd ball lines and try it again.

ARB

HuFlungDung · Feb 8, 2005

No G00 or G01 command for the first positioning move? If a G01 is used before the G83, the feedrate may need to be issued with it early on.

Newbie · Feb 8, 2005

ARB,

or anyone else, how do you use a dwell command?
My manual doesn't tell me much else other than that G04 is the commmand for dwell is the command, but how do I implement it?

Thanks

3t3d · Feb 8, 2005

Dwell...
I don't know about a system 20, but the predecessor, the system 5 used an F to set the time in seconds...

So, a
G04 F20.0
Will dwell for 20 seconds.

I have an Acramatic that will either dwell for
F seconds or
S revolutions

I don't know if the System 20 can dwell for S revolutions, but I suspect that it can dwell for F seconds.

Pete

ARB · Feb 8, 2005

Newbie,

Are you able to get the program into the control? I got to thinking that maybe you are simply having trouble getting the program in. Some controls need certain formatting to load a program through rs232 or floppy.

If you simply want to drill some holes try this.
g90
s500m3
m8
g83 X3.0709 Y0.9843 Z.25K.125R.125Q.1F2.
X7.0079
(continue listing coordinates line by line)
G80
M05
M09
M02

This should work.

In another week I will be able to help more. We are getting a machine in with the Delta 20 control.

Also note that I added a Decimal after the f2 in your g83 line. Some controls can be fussy like that.

Let us know if you are having any luck.

Take Care,

ARB

Dead Nuts · Feb 9, 2005

I have a Dynapath 10 control and the first line is N1000. Don't know if the 20 starts at N0001?

Wouldn't line N001 be the same as N0010 ?

Did you end the program with M30?

[ 02-09-2005, 11:58 AM: Message edited by: Glenn_L ]

Newbie · Feb 9, 2005

Hey whats up,

Yeah so I followed suggestions from Doug and fastolds and got the thing working finally. The main thing was the spaces. That was really messing things up. The boss bought two more CNC and they will be here today, Delta 30CNC.

Hey thanks a lot guys.

Newbie · Feb 10, 2005

Hey I'm back.

Turns out we got 2 new CNCs and one of them had a busted controller, so we are looking for another one. I need some suggestions on what to get. We have a Delta 20CNC, just got a Delta 10CNC. Any suggestions? Anyone know what the difference is between Delta 10,20,30?

Let me know.

Michael Moore · Feb 10, 2005

Have you checked with Dynapath to see what kind of support they can supply on the older controls?

http://www.dynapath.com/page_all.htm

cheers,
Michael

3t3d · Feb 11, 2005

Parts and Smarts supports ALL the old Bendix, Dynapath, and Autocon controls. They typicaly buy up the remainaing factory inventory when the factory no longer wants to support a line.

Julius or Al is VERY knowledgeable and helpfull.
877-394-5249
800-967-0932

No worries about support from them.
Pete

6handicap · Mar 1, 2005

Delta 10,20,30
The delta 10 and 20 were disigned and built by Dynapath. The major difference was in the processor. The Delta 10 had one processor and could not DNC The processor executed the program and controlled machine funtions. The Delta 20 had 2 processors, one to execute the program and control machine functions, the second controlled communication and memory management, which allowed DNC.
The Delta 30/40/50 was a departure from the Dynapath designed architecture and incorporated a PC based architecture, I believe the early ones were 486 based processors with the typical pc mother board and i/o structure.

As far as being busted, would need additional info to help with that LOL. Unless paint will fix it.
AL

loghan · Jul 18, 2005

I know how to program dynapath 10 20 and 40
can be emailed at [email protected] to get phone # if you still need help .

dsergison · Jul 18, 2005

great to hear you got it fixed. I have one too. I have been having the same sorts of questions.

deffinately no lower case characters allowed.

that was your problem. otherwise you can at least run in graphics mode and it will tell you which line # is the problem.

the line #s can only go to N9999 but you can use decimals to at least one place maybe 2 or more (N9999.9) etc...

(post directed at posterities sake, you may already have figured that out)

fredj · Jul 18, 2005

I program and run the delta20 every day its a solid control
I read the (test) 4 times still didn't catch the spaces problem.
using Gibbs to create the code, then predator editor to get it in to the control I forgot that i have it set up to stip the spaces as it send it to the control.

mcpgmr · Nov 17, 2005

I'm new to the forum so I'd like to say hello to everyone here. I have run and programmed the delta 20 years ago and am back to tinkering with one. I use Mastercam to program and use the MC supplied post to generate code. The format looks somthing like this.

(207C9204-P2_REV-B_OP1)
N5(9)M08$
N10(9)M03T01$
N15(T)FACETOPT$
N20(0)X5.175Y-0.375Z2.$
N25(0)Z0.1$
N30(1)Z-0.145F10.0$
N35(1)X4.575F41.3$
N40(1)X0.$
N45(1)X-0.6$
N50(0)Z0.25$
N55(0)X5.175$
N60(9)M03$
N65(0)X5.175Y-0.375Z-0.045$
N70(1)Z-0.29F10.0$
N75(1)X4.575F41.3$
N80(1)X0.$
N85(1)X-0.6$
N90(0)Z0.25$
N95(0)X5.175$
N100(9)M03$
N105(0)X5.175Y-0.375Z-0.19$
N110(1)Z-0.3F10.0$
N115(1)X4.575F41.3$
N120(1)X0.$
N125(1)X-0.6$
N130(0)Z2.$
N135(9)M09$
N140(9)M06T02$
N145(T)RFANDFIN$
N150(9)M08$
N155(9)M03T02$
N160(0)X-0.1975Y-0.9875Z2.$
N165(0)Z0.1$
N170(1)Z-0.6F20.0$
N175(1)Y-0.6875F48.0C1$
N180(1)Y-0.0625$
N185(2)X0.0625Y0.1975I.0625J-.0625D0$
N190(1)X4.5125$
N195(2)X4.7725Y-0.0625I4.5125J-.0625D0$
N200(1)Y-0.6875$
N205(2)X4.5125Y-0.9475I4.5125J-.6875D0$
N210(1)X0.0625$
N215(2)X-0.1975Y-0.6875I.0625J-.6875D0$
N220(1)X-0.4975C0$
N225(0)Z0.25$
N230(0)X-0.1875Y-0.9875$
N235(9)M03$
N240(0)X-0.1875Y-0.9875Z0.1$
N245(1)Z-0.6F20.0$
N250(1)Y-0.6875F48.0C1$
N255(1)Y-0.0625$
N260(2)X0.0625Y0.1875I.0625J-.0625D0$
N265(1)X4.5125$
N270(2)X4.7625Y-0.0625I4.5125J-.0625D0$
N275(1)Y-0.6875$
N280(2)X4.5125Y-0.9375I4.5125J-.6875D0$
N285(1)X0.0625$
N290(2)X-0.1875Y-0.6875I.0625J-.6875D0$
N295(1)X-0.4875C0$
N300(0)Z2.$
N305(9)M30$
END

CBlair · Nov 17, 2005

Welcome aboard, thanks for the code.

Charles

dragonsgj · Nov 19, 2005

This is a little off-topic, but I thought I'd ask: I use Mastercam to write the programs for my Dynapath Delta 20 controlled machine, but I have always preferred Edgecam. Does anyone have a post processor, or a post that I can change in Code Wizard and edit for a Dynapath 20?

micro · Nov 24, 2005

I program and run the delta20 every day its a solid control
I read the (test) 4 times still didn't catch the spaces problem.
using Gibbs to create the code, then predator editor to get it in to the control I forgot that i have it set up to stip the spaces as it send it to the control.

Fred,
Are you using predator for your everyday program to control download, or just for drip feeding? Have you used Gibbs download feature? For programs small enough to fit in the control memory I find that the Gibbs communication feature works great. Very convenient.

fredj · Nov 26, 2005

Micro
Correct on prediator, Iam useing it for the editing and communication. Have not used the gibbs feature.
i like changeing the colors for each axis,m codes ,feed ,tool and g code.
all different colors makes it easyer for my old eyes to read.
i have both on my laptop at the machines i program and run.

Dynapath Delta 20CNC

Plastic

Titanium

Diamond

Plastic

Diamond

Titanium

Cast Iron

Plastic

Plastic

Titanium

Diamond

Banned

Plastic

Diamond

Aluminum

Plastic

Diamond

Plastic

Stainless

Aluminum