Renishaw Inspection Plus software for Mazak

[M Code]

Hi

For VCN machine we have Renishaw Inspection Plus software, however in Fanuc I use probe cycles for updating the WCS i was building the cycle starting from select the WCS and positioning then protected move after that start the cycle, that the usual way I was doing in Fanuc, in Mazak new controls the machines come with Renishaw Inspection Plus software which is an interface and the operator can build the cycle based on selections.

I want to write the probe cycle in the main program without using the interface I know how to write the main cycle like G65P9901 M** C** X** etc.. but I don't know what to put before and after it. If any one can help and give me example for that I went to the catalog and didn't find anything.

Thanks ....

 

[sakis]

Sounds like your trying to use goprobe cycles. They are really meant to be ran from position in mdi although you might be able to use the in automatic. I think to use them in auto you need to add C1. To every call. You probably have the inspection plus cycles I woul just use them instead

 

[13engines]

Realize that inspection Plus and GoProbe are two different pieces of software. Regardless... GoProbe is an overlay interface that deep down inside calls Inspection Plus routines. Simple enough to see if program 9901 is present in the control. If so you've got Go Probe.

GoProbe works fine in automatic mode. (My experience is with Fanuc)

You simply call the probe like any other tool with an initial position move, activate the probes G43 height offset stopping at a clearance plane, then call your G65P9901M etc routine including C1. with every iteration and C0. within the last one.

Here's an example off the top of my head. Updating two existing offsets relative to an existing bore.

T30M6 (PROBE)
G17G20G49G54G80G90G98

G0X1.3Y-0.625
G43Z0.5H30T1
G65P9901M2.C1.X1.3Y-0.625Z-0.25D0.75S54.
G55
G65P9901M2.C0.X1.3Y-0.625Z-0.25D0.75S55.
G53Z0.(for added finishing safety)

T1M6 (END MILL)
.....................................................

Don't have my books with me so can't remember if/when you also need IJK included.

Only trouble I've experienced using GoProbe (Mori/Fanuc) in automatic is when I'm using a Z (A-3) in a routine. It keeps shutting off my probe after every routine. C1. or not. The folks at Renishaw and I have not yet found a solution to that problem.

 

[M Code]

Realize that inspection Plus and GoProbe are two different pieces of software. Regardless... GoProbe is an overlay interface that deep down inside calls Inspection Plus routines. Simple enough to see if program 9901 is present in the control. If so you've got Go Probe.

GoProbe works fine in automatic mode. (My experience is with Fanuc)

You simply call the probe like any other tool with an initial position move, activate the probes G43 height offset stopping at a clearance plane, then call your G65P9901M etc routine including C1. with every iteration and C0. within the last one.

Here's an example off the top of my head. Updating two existing offsets relative to an existing bore.

T30M6 (PROBE)
G17G20G49G54G80G90G98

G0X1.3Y-0.625
G43Z0.5H30T1
G65P9901M2.C1.X1.3Y-0.625Z-0.25D0.75S54.
G55
G65P9901M2.C0.X1.3Y-0.625Z-0.25D0.75S55.
G53Z0.(for added finishing safety)

T1M6 (END MILL)
.....................................................

Don't have my books with me so can't remember if/when you also need IJK included.

Only trouble I've experienced using GoProbe (Mori/Fanuc) in automatic is when I'm using a Z (A-3) in a routine. It keeps shutting off my probe after every routine. C1. or not. The folks at Renishaw and I have not yet found a solution to that problem.

Thanks you so much sir


The question now
if we use
G65P9901M***.C***.X**.Y***D***5S***.
and
G65P9814D3.0 S1.0

is the first one belongs to Go probe and the other one for another method?

 

[13engines]

Yes. The other is Inspection Plus.

As long as you're following all the rules of syntax and input demands, you can mix and match the two call types all you want.