Fanuc 6T Post
Close
Login to Your Account
Likes Likes:  0
Results 1 to 17 of 17

Thread: Fanuc 6T Post

  1. #1
    Join Date
    Jun 2018
    Country
    CANADA
    State/Province
    Quebec
    Posts
    29
    Post Thanks / Like
    Likes (Given)
    0
    Likes (Received)
    1

    Default Fanuc 6T Post

    Hi

    I have a fanuc 6T control on a Nakumara TMC4. I purchased Mastercam recently and they provided me a generic post however it does not match my machine.
    So I am wondering if somebody may have some examples of the G-code format. I do have a manual but it dates back to 1980

    This much i know its a single line I did manage to find this one in the past and it works

    G71 P (?) Q (?)U.05 W.005 D1500 F.015

  2. #2
    Join Date
    Jun 2011
    Country
    UNITED STATES
    State/Province
    New Jersey
    Posts
    1,264
    Post Thanks / Like
    Likes (Given)
    737
    Likes (Received)
    512

    Default

    Quote Originally Posted by cookie54 View Post
    Hi

    I have a fanuc 6T control on a Nakumara TMC4. I purchased Mastercam recently and they provided me a generic post however it does not match my machine.
    So I am wondering if somebody may have some examples of the G-code format. I do have a manual but it dates back to 1980

    This much i know its a single line I did manage to find this one in the past and it works

    G71 P (?) Q (?)U.05 W.005 D1500 F.015
    The 1980 manual is correct for the 6T. 6, 10, 11, 12, and many 15 use the single line cycles. Some 15, and most 16, 18, 21, 32, 31, 30, and 0 use the two line cycles.

    You'll probably need to have them cook up a post as the older controls have been out of production for so long.

  3. #3
    Join Date
    Oct 2009
    Location
    Oregon
    Posts
    5,444
    Post Thanks / Like
    Likes (Given)
    5888
    Likes (Received)
    2901

    Default

    I have Mastercam, but I purchased it used 12 years ago.

    "I purchased mastercam for me 6T..." Doesn't seem right. Why? You had to've paid more for the software than the machine, right?

    Lathe code is pretty simple. If mastercam is spitting out wrong code I can't imagine tweaking it by hand is so hard?

  4. #4
    Join Date
    Jan 2019
    Country
    UNITED STATES
    State/Province
    Missouri
    Posts
    279
    Post Thanks / Like
    Likes (Given)
    83
    Likes (Received)
    66

    Default

    You could always, just not use canned roughing. Until you figure it out.

  5. #5
    Join Date
    Jan 2013
    Location
    Gilbert, AZ
    Posts
    6,767
    Post Thanks / Like
    Likes (Given)
    8740
    Likes (Received)
    8738

    Default

    Quote Originally Posted by GENERALDISARRAY View Post
    You could always, just not use canned roughing. Until you figure it out.
    I never used canned cycles in my 6T because I was never able to make it work.

  6. #6
    Join Date
    Jun 2011
    Country
    UNITED STATES
    State/Province
    New Jersey
    Posts
    1,264
    Post Thanks / Like
    Likes (Given)
    737
    Likes (Received)
    512

    Default

    Quote Originally Posted by wheelieking71 View Post
    I never used canned cycles in my 6T because I was never able to make it work.
    Really?
    I had an old 6T-B and the one line canned cycles worked ok. Same as my 10's and 11's.

  7. #7
    Join Date
    Jul 2013
    Location
    Indiana
    Posts
    3,369
    Post Thanks / Like
    Likes (Given)
    4933
    Likes (Received)
    1727

    Default

    No type 2 roughing with the 6T but other than that the canned cycles work pretty much the same. Two line G76 is different.

    Brent

  8. #8
    Join Date
    Sep 2010
    Location
    Victoria Australia
    Posts
    3,985
    Post Thanks / Like
    Likes (Given)
    0
    Likes (Received)
    1638

    Default

    Quote Originally Posted by yardbird View Post
    No type 2 roughing with the 6T but other than that the canned cycles work pretty much the same. Two line G76 is different.

    Brent
    Hello Brent,
    Type II was available with the 6T Model B.

    Regards,

    Bill

  9. #9
    Join Date
    Jun 2018
    Country
    CANADA
    State/Province
    Quebec
    Posts
    29
    Post Thanks / Like
    Likes (Given)
    0
    Likes (Received)
    1

    Default 6T post issue

    Hi DouglasJRizzo & Wheelieking

    Your right about the post i will get one to fit my machine. The generic on spits out

    3 axis instead of 2 only

    It doesn't make the G50 X0.0 Z0.0 to work with G28 U0.0 W0.0

    I would like it to do a M5 before it goes to G0G28U0.0 W0.0 if not the spingle ramps up in full RPM till it hits machine 0 then it shuts off
    I tried a threading cycle and for some reason it throws a A58 in the threading cycle instead of a A60 the machine faulted again the manual requires A60

    If I idle the machine in M41 spindle low range (Warm Up) Start the program that needs to be in M42 the machine wont shift and wont run but i can shift with the control panel. Does this machine have to be running for a gearbox change from low to high?

    regards
    Eric

  10. #10
    Join Date
    Sep 2010
    Location
    Victoria Australia
    Posts
    3,985
    Post Thanks / Like
    Likes (Given)
    0
    Likes (Received)
    1638

    Default

    Quote Originally Posted by cookie54 View Post
    Hi DouglasJRizzo & Wheelieking

    Your right about the post i will get one to fit my machine. The generic on spits out

    3 axis instead of 2 only

    It doesn't make the G50 X0.0 Z0.0 to work with G28 U0.0 W0.0

    I would like it to do a M5 before it goes to G0G28U0.0 W0.0 if not the spingle ramps up in full RPM till it hits machine 0 then it shuts off
    I tried a threading cycle and for some reason it throws a A58 in the threading cycle instead of a A60 the machine faulted again the manual requires A60

    If I idle the machine in M41 spindle low range (Warm Up) Start the program that needs to be in M42 the machine wont shift and wont run but i can shift with the control panel. Does this machine have to be running for a gearbox change from low to high?

    regards
    Eric
    Hello Eric,
    With regards to the threading cycle, I assume G76, are you saying that the machine actually alarms when A58 is specified, or do you mean that the A58 is the error? It may be your interpretation that the manual requires A60, but I doubt that the manual actually says that. Specifying A58 for the included angle of a 60deg Threading Tool is quite legal with the 6T control, even with the model A; the allowable angles are Zero to 120degs in increments of 1deg. The control only knows the included angle of the tool by what is specified by address A in the program and as long as an angle between Zero and 120degs is specified (in increments of 1deg.) then there should be no issue.

    Its quite a common practice to specify an angle that is a few degrees less than the actual included angle of the Threading Tool, particularly on coarse pitched threads that will have a corresponding large thread height. The reason being is that when the actual included angle of the Threading Tool is specified, all of the cutting will be done with the leading edge of the insert and it can result is a slightly stepped and poor finish on the trailing flank of the thread form. By specifying an included angle slightly less than the actual Threading Tool, most of the cutting will be done by the leading edge of the tool and a slight amount by the trailing edge.

    It would be better if you were to Post examples of your code so that the Forum members can give you more informed answers.

    Regards,

    Bill

  11. #11
    Join Date
    Jan 2019
    Country
    UNITED STATES
    State/Province
    Missouri
    Posts
    279
    Post Thanks / Like
    Likes (Given)
    83
    Likes (Received)
    66

    Default

    Quote Originally Posted by cookie54 View Post
    Hi DouglasJRizzo & Wheelieking

    Your right about the post i will get one to fit my machine. The generic on spits out

    3 axis instead of 2 only
    Have you tried

    LATHE 2-AXIS SLANT BED.mcam-lmd

  12. #12
    Join Date
    Jun 2018
    Country
    CANADA
    State/Province
    Quebec
    Posts
    29
    Post Thanks / Like
    Likes (Given)
    0
    Likes (Received)
    1

    Default

    Hi Everybody,

    In regards to my threading program here is the code for discussion

    M42
    N5T0100
    (OD THREAD RIGHT)
    (MAX - Z-.036 MIN - Z-.8925)
    G98
    G97S200M03
    G0X1.5125Z-.036M08T0101
    G76X1.2352Z-.8925I0.K0387D0150A60F.0714
    M09
    G50X0.Z0.
    G0G28U0.W0.
    T0100
    M05
    M01

    (BORE ID)
    G0G28U0.W0.
    G50X0.Z0.
    M42
    N6T0800


    With the A58 angle the machine would Index the turret and go to the position of starting the thread cycle and then block and give a program alarm 060 Program

    By changing the A58 to A60 the lathe would cycle through.

    The A 58 came from MasterCam it was set up in the Parameters. 29 degree lead angle. I attached the a copy of the manual

    I got my Post modified now.


    023127.jpg023224.jpg

  13. #13
    Join Date
    Sep 2010
    Location
    Victoria Australia
    Posts
    3,985
    Post Thanks / Like
    Likes (Given)
    0
    Likes (Received)
    1638

    Default

    Quote Originally Posted by cookie54 View Post
    Hi Everybody,

    In regards to my threading program here is the code for discussion

    M42
    N5T0100
    (OD THREAD RIGHT)
    (MAX - Z-.036 MIN - Z-.8925)
    G98
    G97S200M03
    G0X1.5125Z-.036M08T0101
    G76X1.2352Z-.8925I0.K0387D0150A60F.0714
    M09
    G50X0.Z0.
    G0G28U0.W0.
    T0100
    M05
    M01

    (BORE ID)
    G0G28U0.W0.
    G50X0.Z0.
    M42
    N6T0800


    With the A58 angle the machine would Index the turret and go to the position of starting the thread cycle and then block and give a program alarm 060 Program

    By changing the A58 to A60 the lathe would cycle through.

    The A 58 came from MasterCam it was set up in the Parameters. 29 degree lead angle. I attached the a copy of the manual
    Hello Eric,
    That's an unusual alarm number to be raised for an issue relating to the included angle of the thread form specified, because p/s060 is normally raised for the following reason:

    "Commanded sequence number was not found in the sequence number search."

    See the extract from Fanuc 6T manual following:

    6t-060-alarm1.jpg

    So I think this is an issue peculiar to your machine.



    Regards,

    Bill
    Last edited by angelw; 10-23-2020 at 04:07 AM.

  14. #14
    Join Date
    Jun 2018
    Country
    CANADA
    State/Province
    Quebec
    Posts
    29
    Post Thanks / Like
    Likes (Given)
    0
    Likes (Received)
    1

    Default

    Hi Bill,

    Sorry for the mistake I provided the wrong error code

    Went back and double checked the machine and found that it is actually 062 Program

    Regards,
    Eric

  15. #15
    Join Date
    Sep 2010
    Location
    Victoria Australia
    Posts
    3,985
    Post Thanks / Like
    Likes (Given)
    0
    Likes (Received)
    1638

    Default

    Quote Originally Posted by cookie54 View Post
    Hi Bill,

    Sorry for the mistake I provided the wrong error code

    Went back and double checked the machine and found that it is actually 062 Program

    Regards,
    Eric
    Hello Eric,
    That makes more sense. I suspect that your control is quite an early build of the 6T Model A control. When in memory mode, do you see a whole page of code (when you have the program page selected), or just the current and pending Block? If not a whole page, then the control is a Model A. Another telltale of the Model B, if the plate has not been lost, is a Yellow Fanuc plaque attached to the front of the control; the plaque of the Model A is white.

    Actually, I thought the FS5T control was able to use any angle, in increments of 1deg, between Zero and 120deg, but it can only use the angles 0, 29, 30, 55, 60 and 80, the same as listed in your manual. There was a lot of carry forward from the FS5T control, including the same, seven segment LED display and no CTR screen for the very early FS6T controls. For the reason give in my earlier Post, it's still a common practice to specify an angle of 55degs, when cutting a Thread using a tool with an included angle of 60deg.

    Regards,

    Bill

  16. #16
    Join Date
    Jun 2012
    Location
    Michigan
    Posts
    5,457
    Post Thanks / Like
    Likes (Given)
    5115
    Likes (Received)
    3429

    Default

    Quote Originally Posted by cookie54 View Post
    I have a fanuc 6T control on a Nakumara TMC4. I purchased Mastercam recently and they provided me a generic post however it does not match my machine.
    So.... why don't you call them and get it sorted out?

  17. #17
    Join Date
    Jun 2018
    Country
    CANADA
    State/Province
    Quebec
    Posts
    29
    Post Thanks / Like
    Likes (Given)
    0
    Likes (Received)
    1

    Default

    Hi Bill

    The machine produces the whole page on the screen and there is also a white plate at the bottom of the control panel.

    It has a Model number starting with A02B- 00 It was made in November 1980

    Regards
    Eric


Tags for this Thread

Bookmarks

Posting Permissions

  • You may not post new threads
  • You may not post replies
  • You may not post attachments
  • You may not edit your posts
  •