I have an MX2 A.G.E. bed mill. I inherited from my uncle last year. I use it as a hobby in my garage. I'm familiar with the machine and the capabilities of it. I have Mastercam and Millwrite available to me to use at anytime. Basically, what I'm getting at is I can't get the laptop to connect to the rs232 to have the program transferred properly. I'm using a usb to rs232 db25 connector with a null modem adadpter from Cable 2 Go. It will transfer but 1 of 2 things will happen. With engraving, it will only repeat the first letter for the length of the program or only about 75% will be transferred. Also, I bought a 3.5 external floppy writer so I could transfer that way... it can't read ".cam" files through the mx2 floppy port. After discussing with SWI, it's an up gradable feature for $425 to get a 3.5 floppy with the "MX2e" boot up floppy. I will not pay that much for 24 year old technology for something I don't make money with. If you have any tips or tricks please let me know. Thank you in advanced.
.
must be setup on computer
4800, e, 7, 1
.
if you use different serial port setting it will not transfer file
.
Gcode must be on every line
Gcode must have space between them
End of Block character must be semicolon (this often will stop program at 1st line cause stuck and will not read next line, end of block is end of line) so adding semi colon to each end of line is needed if post processor does not do it. i have change it in mastercam to add semi colon automatically to each end of line. takes time figuring it out. it is a mastercam thing
.
it prefers prototrak gcode but often Fanuc 6 gcode it will read and translate but will need testing
.
Fanuc 6 is 2 axis it does not see Z and thus no Z axis will be translated
.
MX2 and AGE2 are different. some AGE will translate Fanuc much better than earlier MX2 or Prototrak Plus models
.
file size limit is a little over 200 lines
.
i have used edytornc software to file transfer. you will need to check and change default settings to 4800, e, 7, 1
.
mastercam has file editors that will file transfer too but again you need to check default settings
.
EdytorNC download | SourceForge.net