Okuma probing

We have two OKUMA MX45VAE OSP700M have Renishaw MP-10 probes. I use the renishaw on our haas and am familiar with it, but have never used them on our okumas. I was wondering if anyone has an example program for the probe. Looking to probe Z, X-web, and Y-web for zero.

$probe-plate-xyz.min%
(vc1=h offset)
(vc2=x location for z)
(vc3=y location for z)
(vc4=plate length in x)
(vc5=pin distance over side to probe xy positive number)
(vc6= plate length in y)
g116 t19
g15 h[vc1] (activate offset)
g56 h19 (activate tlo: Set offset same as calibration value)
g0 x[vc2] y[vc3] z5.
Z2.
M130
g1 z.5 f20.
M127
call oo18 (probe on)
call oo10 pmod=3 pei=-.25 (probe z -.250" from present position)
call oo20 phn=[vc1] pz=0
()
g0 z2.0
x0
(pmod=11 - move x axis only)
(peli=length of plate)
(pin=distance to drop down over each side)
call oo10 pmod=11 peli=[vc4] pin=[vc5]+2.
Call oo20 phn=[vc1] px=0
g0z2.
X0
z2.
()
call oo10 pmod=12 peli=[vc6] pin=[vc5]+2
call oo20 phn=[vc1] py=0
g0z1.
()
call oo19
g30 p1
m02
%

SMT said:

$probe-plate-xyz.min%
(vc1=h offset)
(vc2=x location for z)
(vc3=y location for z)
(vc4=plate length in x)
(vc5=pin distance over side to probe xy positive number)
(vc6= plate length in y)
g116 t19
g15 h[vc1] (activate offset)
g56 h19 (activate tlo: Set offset same as calibration value)
g0 x[vc2] y[vc3] z5.
Z2.
M130
g1 z.5 f20.
M127
call oo18 (probe on)
call oo10 pmod=3 pei=-.25 (probe z -.250" from present position)
call oo20 phn=[vc1] pz=0
()
g0 z2.0
x0
(pmod=11 - move x axis only)
(peli=length of plate)
(pin=distance to drop down over each side)
call oo10 pmod=11 peli=[vc4] pin=[vc5]+2.
Call oo20 phn=[vc1] px=0
g0z2.
X0
z2.
()
call oo10 pmod=12 peli=[vc6] pin=[vc5]+2
call oo20 phn=[vc1] py=0
g0z1.
()
call oo19
g30 p1
m02
%

Click to expand...

I found our manual and this is what I have so far:

$O3333.MIN%
(PROBE TEE)
(CREATED BY KF)
(DNCID617203)
(OKUMA OSP7000M)
(ORIGIN: X0Y0 CENTER PART, Z0 TOP)
(WORK OFFSET: H1)
(DATE - JUNE-17-2020)
(TIME - 1:04 PM)
G20 G90 G80 G40 G00
(PROBE TEE)
N1 (PROBE)
IF[VTLCN EQ 1] NS11
T25 M06
NS11 G00 Z25.
M01
G15 H20
G00 G90 A0. X0. Y0.
G56 H25 Z1.
M130
G1 Z.1 F25.
M131
(SET Z ZERO TEMP)
CALL OO10 PMOD=3 PEI=-.1
CALL 0020 PHN20 Z0.
M130
G1 Z.1 F25.
M131
(SET Y ZERO)
CALL OO10 PMOD=12 PELI=.509 PIN=-.25
CALL OO20 PHN=20 Y0.
M130
G1 Z.1 F25.
M131
(SET X ZERO TEMP)
CALL OO10 PMOD=11 PELI=1.355 PIN=-.6775
CALL OO20 PHN=20 X0.
M130
G1 Z.1 F25.
M131
(SET Z ZERO FINAL)
CALL OO10 PMOD=3 PEI=-.1
CALL 0020 PHN20 Z0.
M130
G1 Z.1 F25.
M131
(SET X ZERO FINAL)
CALL OO10 PMOD=11 PELI=1.355 PIN=-.6775
CALL OO20 PHN=20 X0.
G00 Z.25
Z1.
G00 Z25.
M30
%

But I am stuck right now trying to set the probe tool length offset. We touched off the top of the part like normal with the reference tool. I have this for a program but it keeps alarming out, it will start the sub routine for setting but then alarm. I am confused with the PEI and PLI for this.

$O3333.MIN%
(SET PROBE TOOL LENGTH OFFSET)
(CREATED BY KF)
(DNCID617201)
(OKUMA OSP7000M)
(ORIGIN: X0Y0 CENTER PART, Z0 TOP)
(WORK OFFSET: H1)
(DATE - JUNE-17-2020)
(TIME - 1:04 PM)
G20 G90 G80 G40 G00
N1 (PROBE)
IF[VTLCN EQ 1] NS11
T25 M06
NS11 G00 Z25.
M01
G15 H1
G00 G90 A0. X0. Y0.
G56 H25 Z1.
CALL OO10 PMOD=8 PEI=? PLI=?
G00 Z.25
Z1.
G00 Z25.
M30
%
Any advice on that?

Sure. First though, you don't have to M130/M131 all the time. Just turn it on and leave it, no reason to turn it off.

To set the length, set Z0 on a part using a tool of known length. Tool change to your probe and turn it on in MDI. You should be able to touch the probe tip and see the lights on the receiver blink to indicate it's triggered.

In mid-auto-manual (so the probe stays on) wheel it down to your part until you click it Z-.0001 and it will trigger the probe and Z+.0001 will untrigger the probe.

Go to your tool data page and calc 0. Probe is then set.

I think its good to know the Okuma cycles.

That being said I'm about 99% sure Renishaw Set and Inspect is standard on the 5ax machines (run several, all had it, and i've seen it listed as standard on the quote for the machine). Its s breeze to use and has a nice GUI.

SMT said:

Sure. First though, you don't have to M130/M131 all the time. Just turn it on and leave it, no reason to turn it off.

To set the length, set Z0 on a part using a tool of known length. Tool change to your probe and turn it on in MDI. You should be able to touch the probe tip and see the lights on the receiver blink to indicate it's triggered.

In mid-auto-manual (so the probe stays on) wheel it down to your part until you click it Z-.0001 and it will trigger the probe and Z+.0001 will untrigger the probe.

Go to your tool data page and calc 0. Probe is then set.

Click to expand...

Hello

Can yyou help me with a problem in my okuma
i dont have renishaw for tool measurement but i habe toutch probe for piece centering,for measure the tool lenght i use a dial and i measure the distance between the top of the tool ans the top of spindle, its ok but when i do z0 with the toutch probe and follow with one tool i have 1 mm diference, do you know why?

I know you have to call a tool offset for the probe when using a manual touch-off like a Haimer 3D taster. I had to run my machine for a few weeks before the probing was installed and now have G15 H99 set for the length of my Haimer.