please give me a ballpark notion of cost to run 10,000 of this part.
Close
Login to Your Account
Page 1 of 7 123 ... LastLast
Results 1 to 20 of 121
  1. #1
    Join Date
    Jun 2006
    Location
    Near Seattle
    Posts
    4,951
    Post Thanks / Like
    Likes (Given)
    3403
    Likes (Received)
    1418

    Default please give me a ballpark notion of cost to run 10,000 of this part.

    Some folks I've been helping are applying for a grant soon (they're part of a university lab.) Their device is a covid-19 test device, a quite inexpensive one. One component of it is an aluminum heat block - I've made about a dozen of these for them. These are to be machined from solid, 6061-T6.

    The grant request for proposal is asking for 10,000 units of their machine, and thus 10,000 units of the component in the attached drawing. I'm a protoypes/experiments for self and friends guy, NOT a "make 10,000 of these" sort of operation. But a number of you lot ARE.

    This is NOT an RFQ - that can't happen until they get the grant. What I am asking for is a ballpark number per unit, in quantity 10K (really), to be starting after the grant is issued (presumably soon), and ready for "the fall" which I gather means september.

    Ballpark costs for that kind of volume? (The point being to ask for enough money in the grant to actually buy the parts.)

    If you think you have some cost advantage in making such parts you don't want to reveal, feel free to PM me.

    Here's a tiny thumbnail to get under the size limit (very hard to get it down to size for some reason):
    thumbnail.jpg


    And here's a link to a normal .pdf you can actually see:
    http://bryanwi.com/WebPix/heatingblockdrawing.pdf

  2. #2
    Join Date
    Jul 2006
    Location
    Hillsboro, New Hampshire
    Posts
    9,200
    Post Thanks / Like
    Likes (Given)
    2184
    Likes (Received)
    6376

    Default

    If some allowance can be made for surface finish in the 17.3 tapered bores and not requiring perfection in the deburring department (the small intersecting holes can be a pain) then I'd think around $2/ea @10K wouldn't be outrageous. If a smoother taper bore was needed to prevent risk of scraping the vials and better finishing, then closer to $3-4/ea.

    I'm curious how others view it. I did a preliminary quote for a larger (but similar purpose) devise a month ago, so have some appreciation for what goes into these things.

  3. Likes bryan_machine, Jashley73 liked this post
  4. #3
    Join Date
    Jul 2006
    Location
    Hillsboro, New Hampshire
    Posts
    9,200
    Post Thanks / Like
    Likes (Given)
    2184
    Likes (Received)
    6376

    Default

    There's something I don't understand about the print. The depth of the taper section is x.x, but the depth of the 3mm cbore below it is x.xx.

    I'd think the taper would dominate insertion depth, so why bother controlling the cbore to a tighter degree? I must not grok how that's being used.

  5. #4
    Join Date
    Nov 2013
    Country
    UNITED STATES
    State/Province
    Utah
    Posts
    4,876
    Post Thanks / Like
    Likes (Given)
    1289
    Likes (Received)
    2755

    Default

    Clear throat Milland you're calling that a 2-3 minute part. not me.

    R

  6. #5
    Join Date
    Jun 2006
    Location
    Near Seattle
    Posts
    4,951
    Post Thanks / Like
    Likes (Given)
    3403
    Likes (Received)
    1418

    Default

    The nominal depth of the taper is indeed 13.5mm, and +-0.1mm is fine, but the dominating issue how the "gauge" fits. The clearence bore at the bottom is NOT so critical, I just missed that when I convereted the drawing.
    (This is prelim.)

    Litlerob1 - you end up touch 3 sides tool on (drilling, milling pockets, etc.) and milling (side milling at least) all 6 sides - but any 5-axis or even 5-axis horizontal can do it in 2 setups. But I've no clue how fast it can go in real production, which I started this thread.

  7. #6
    Join Date
    Mar 2013
    Country
    UNITED STATES
    State/Province
    Oregon
    Posts
    2,016
    Post Thanks / Like
    Likes (Given)
    816
    Likes (Received)
    2472

    Default

    Quote Originally Posted by litlerob1 View Post
    Clear throat Milland you're calling that a 2-3 minute part. not me.

    R
    That is a 1:30 part, on a 4th, in a Speedio, with some custom tooling.

  8. #7
    Join Date
    Jul 2006
    Location
    Hillsboro, New Hampshire
    Posts
    9,200
    Post Thanks / Like
    Likes (Given)
    2184
    Likes (Received)
    6376

    Default

    Quote Originally Posted by litlerob1 View Post
    Clear throat Milland you're calling that a 2-3 minute part. not me.

    R
    Heh - I admit I'm not the best at quoting. But it's a simple part, with two custom cutters (well, more than two, but whatever) to rough and finish the taper bores. I'd probably not make my shop rate, but I tend to go low for university work. It's in my DNA, so to speak.

  9. Likes rcoope, Bobw liked this post
  10. #8
    Join Date
    Nov 2013
    Country
    UNITED STATES
    State/Province
    Utah
    Posts
    4,876
    Post Thanks / Like
    Likes (Given)
    1289
    Likes (Received)
    2755

    Default

    Okay. Ass-you-me-ing we're talking about a Brother MX. And we're talking about doing 5 sides in One set up, and the 6th side on the Second set up....Between toolchanges, B-axis indexing and C-axis rotation, I don't see a 3 minute part. And that's assuming we're talking about the fastest 5 Axis Milling machine out there. But I'm wrong regularly. Nesting a bunch of parts on one pallet, maybe. Just saying, I don't see it.

    R

  11. #9
    Join Date
    Jul 2012
    Country
    UNITED STATES
    State/Province
    Washington
    Posts
    3,074
    Post Thanks / Like
    Likes (Given)
    1231
    Likes (Received)
    1294

    Default

    I am with Milland on the low end, not so sure about going so high on the high end. I see this as a custom tool and the 4th axis job. I am also figuring in on easy payment, like not dicking around paying you, and not that I would be interested in the job. Certainly not a 2 min per part job, as in less, hopefully. 10,000 parts make it worth tooling up for.

  12. #10
    Join Date
    Mar 2013
    Country
    UNITED STATES
    State/Province
    Oregon
    Posts
    2,016
    Post Thanks / Like
    Likes (Given)
    816
    Likes (Received)
    2472

    Default

    Quote Originally Posted by litlerob1 View Post
    Okay. Ass-you-me-ing we're talking about a Brother MX. And we're talking about doing 5 sides in One set up, and the 6th side on the Second set up....Between toolchanges, B-axis indexing and C-axis rotation, I don't see a 3 minute part. And that's assuming we're talking about the fastest 5 Axis Milling machine out there. But I'm wrong regularly. Nesting a bunch of parts on one pallet, maybe. Just saying, I don't see it.

    R
    10k is enough quantity that you get an extrusion dimensioned to the Y direction, so you have 4 sides done to dimension.

    Goes on the 4th clamped across Y and gets done in 1 op. 1/8" Nachi TSC drill hits the 4 through holes and takes the meat out of the cones. 3mm Nachi flat bottom TSC hits the bottom bores. Pair of custom tapered cutters rough and finish the taper bores. 1/4" EM finishes the top and bottom surfaces in a single pass. 3mm end mill does that little pocket.

    I still have 45 seconds left to debur after all that.

    Edited To Add:
    Move it to 1.5 wide by 0.375 thick and you could ditch the need for a custom extrusion. Also, what is the finishing like? Anodize?

  13. Likes DanASM, kazlx, Jashley73 liked this post
  14. #11
    Join Date
    Nov 2013
    Country
    UNITED STATES
    State/Province
    Utah
    Posts
    4,876
    Post Thanks / Like
    Likes (Given)
    1289
    Likes (Received)
    2755

    Default

    Quote Originally Posted by gkoenig View Post
    10k is enough quantity that you get an extrusion dimensioned to the Y direction, so you have 4 sides done to dimension.

    Goes on the 4th clamped across Y and gets done in 1 op. 1/8" Nachi TSC drill hits the 4 through holes and takes the meat out of the cones. 3mm Nachi flat bottom TSC hits the bottom bores. Pair of custom tapered cutters rough and finish the taper bores. 1/4" EM finishes the top and bottom surfaces in a single pass. 3mm end mill does that little pocket.

    I still have 45 seconds left to debur after all that.
    You also have another operation, plus original set-up, plus load and unload. Start to Start time isn't the same as the cycle time the software spits out. If that's how you quote work, you're on hind tit.

    R

  15. #12
    Join Date
    Mar 2013
    Country
    UNITED STATES
    State/Province
    Oregon
    Posts
    2,016
    Post Thanks / Like
    Likes (Given)
    816
    Likes (Received)
    2472

    Default

    Quote Originally Posted by litlerob1 View Post
    You also have another operation, plus original set-up, plus load and unload. Start to Start time isn't the same as the cycle time the software spits out. If that's how you quote work, you're on hind tit.

    R
    What is this other operation you speak of?

  16. #13
    Join Date
    Dec 2003
    Location
    poulsbo, wa, usa
    Posts
    1,025
    Post Thanks / Like
    Likes (Given)
    72
    Likes (Received)
    441

    Default

    looks like 2 opps ,,, 3/8" by 3/4" stock layed flat on a 4th … mitee bite clamps between two strips and do a row of tapers ,, turn 90* and do the side holes and cut down in thickness ,, turn 90 more and do second strip of taper holes ,, then flip back 90* and cut between them …

    Second opp would just be clamp and mill off the extra width and do the bottom pocket in a vise ,,,

    even on a small mill you could run 28.5" strips 2 on each side of a 4th axis ,,,

    that would give you 128 parts per load on the 4th ,,,

  17. #14
    Join Date
    Nov 2013
    Country
    UNITED STATES
    State/Province
    Utah
    Posts
    4,876
    Post Thanks / Like
    Likes (Given)
    1289
    Likes (Received)
    2755

    Default

    Quote Originally Posted by gkoenig View Post
    What is this other operation you speak of?
    You have holes (tapered) 180° from a 5mm slot, than cross holes at 90° of B. If you mean 5 Axis I'll say okay, but I don't see how with 4.

    R

  18. #15
    Join Date
    Nov 2014
    Country
    UNITED STATES
    State/Province
    Florida
    Posts
    4,511
    Post Thanks / Like
    Likes (Given)
    1730
    Likes (Received)
    2161

    Default

    I have to admit, I haven't been a quoting/estimating guy in some years now, but I'm with Rob... 2minutes??? So 30 pcs/hr / 100 hr shop rate (average or so) = 3$ a part!?!? Factor in tooling, programming, setup and maybe average $4/part... Then it is medical so the dr/hospital is going to charge the end user $3-400 HUNDRED for each one... Sounds like a lose lose to me.

  19. Likes SRT Mike liked this post
  20. #16
    Join Date
    Mar 2013
    Country
    UNITED STATES
    State/Province
    Oregon
    Posts
    2,016
    Post Thanks / Like
    Likes (Given)
    816
    Likes (Received)
    2472

    Default

    Quote Originally Posted by litlerob1 View Post
    You have holes (tapered) 180° from a 5mm slot, than cross holes at 90° of B. If you mean 5 Axis I'll say okay, but I don't see how with 4.

    R
    No, I would clamp the part across the narrow dimension (so clamping across the X axis). The tapered holes get addressed at A-90, the 3x5mm slot gets addressed at A90, while the through holes are at A0.

  21. #17
    Join Date
    Jan 2019
    Country
    UNITED STATES
    State/Province
    Arizona
    Posts
    950
    Post Thanks / Like
    Likes (Given)
    84
    Likes (Received)
    345

    Default

    Quote Originally Posted by gkoenig View Post
    No, I would clamp the part across the narrow dimension (so clamping across the X axis). The tapered holes get addressed at A-90, the 3x5mm slot gets addressed at A90, while the through holes are at A0.
    This^^^^
    and to make it even faster buy preground stock (like TCI)in strips that way the only thing your doing is holes depths and cutting to length.
    on a brother and 4th it would haul ass, you would have to debur inside the taper with the cross holes I'd use a nylon bottle brush of some sort in the 1/8 holes to knock the crossburr burrs off.

    then parts come off machine finished.

    I would change the 4th axis to 5 or 6 sided tombstone so to speak instead of a 4 side one. as you need to run as many parts as you can and keep your tool changes to a min. tool changes and part loading is what would take more time than runtime. so load it up to have your runtime more than tool change time.
    Strips would be easy to load and fast. if you have a pallet machine it would be far faster, or make your tombstone so it accepts pallets loaidng and unloading while machine is running.
    the finish is what the problem may or may not be. I am guessing 63 finish to 32 finish in the holes and angled holes thats not a problem. the Breaks where the cross holes meet the tapered Id is key.
    tossing in a tumbler should be a problem.

  22. Likes Joe Miranda liked this post
  23. #18
    Join Date
    Mar 2013
    Country
    UNITED STATES
    State/Province
    Oregon
    Posts
    2,016
    Post Thanks / Like
    Likes (Given)
    816
    Likes (Received)
    2472

    Default

    Quote Originally Posted by Mike1974 View Post
    I have to admit, I haven't been a quoting/estimating guy in some years now, but I'm with Rob... 2minutes??? So 30 pcs/hr / 100 hr shop rate (average or so) = 3$ a part!?!? Factor in tooling, programming, setup and maybe average $4/part... Then it is medical so the dr/hospital is going to charge the end user $3-400 HUNDRED for each one... Sounds like a lose lose to me.
    I think this is a highly machinery dependent quote. If you've got a gaggle of 40x20 CAT40 mills, this is a hard job to make money on. If you have a horizontal, it looks a bit better. If you have a Speedio with a pallet changer and dual trunnion? This is an obvious moneymaker.

    What actually gets quoted is another matter entirely, and is based on factors that aren't in the print. Is this a rush-rush job? What is the finishing process (i.e. how much can we get away with and lean on post-processing for?). Is this 10k and done, or can we get a blanket arrangement in the future going? Is the client gonna pay?

  24. Likes bryan_machine liked this post
  25. #19
    Join Date
    Jul 2006
    Location
    Hillsboro, New Hampshire
    Posts
    9,200
    Post Thanks / Like
    Likes (Given)
    2184
    Likes (Received)
    6376

    Default

    Quote Originally Posted by gkoenig View Post
    What actually gets quoted is another matter entirely, and is based on factors that aren't in the print. Is this a rush-rush job? What is the finishing process (i.e. how much can we get away with and lean on post-processing for?). Is this 10k and done, or can we get a blanket arrangement in the future going? Is the client gonna pay?
    Agreed - there's a lot of unknowns, so we're shooting in the dark. But we have gotten some useful discussion from the "RFQ", so the OP's ballpark request has been met (I'd hope).

    Wait 'til we find out they get sourced from China for $0.50 each...

  26. Likes bryan_machine liked this post
  27. #20
    Join Date
    Apr 2019
    Country
    UNITED STATES
    State/Province
    Arkansas
    Posts
    1,291
    Post Thanks / Like
    Likes (Given)
    565
    Likes (Received)
    491

    Default

    I think most of you are thinking about it the wrong way completely.

    I originally figured running them in the hx250 pallet pool but hell... I think this is a job for the nlx and bar feed it. We did a fiber optic cleave tool component here recently that we moved from the mill to the lathe and cut our cycle time in half when you consider load and unload.

    My software says $1.82 each with custom tooling, liners, collets, etc.

    Who wants to unload 10,000 small parts by hand.





    Sent from my Pixel 3 using Tapatalk


Tags for this Thread

Bookmarks

Posting Permissions

  • You may not post new threads
  • You may not post replies
  • You may not post attachments
  • You may not edit your posts
  •