Thread: Setting Offsets (G54) in ShopTurn with 810D

Edit: I meant to write "Siemens 810D Control" in title. Doesn't look like it's possible to edit titles.


Hi All

New to post here but been here for a while.

For a while now I've been trying to workout if there is a GCode line I can use to set the work offset with ShopTurn on a Siemens 810D control (the machine is a Hardinge).

I've googled it and read some manuals but could never get it to work. I want to just add a line at the top of the program to set the G54 for each program.

For example I'd like to set the Z G54 work offset to 100mm.
In normal gcode that would be something like "G10 L2 P1 G90 Z100.0" I can't get this to work with this control though. Does any one have experience with ShopTurn/Siemens controls?

I'm sure it must be something simple.

Thanks in advance

you can do a

trans z100

its part of the frames concept of seimens. trans by itself will cancel the frame completely. so if you had x or y transformations it cancels them to

My 810D is on an Emco Maier, we use

G58 X0 Z100 (Shift Z100mm)
G58 X0 Z0 (Cancel Z shift)

Thanks for the responses. TRANS puts an offset into the program only which will probably work. I was hoping to be able to set my work offset (G54) from the program and it stay set even after the program ends.

SIM, G58 doesn't do anything, is G58 the work offset that you use or do you use G58 as a means to set a work offset? Either way my machine errored out when I tried "G58 X0 Z100."

Off topic but do either of you use a network/computer attached to your Siemens 810D (I've never managed to get it to work)?

try this


$P_UIFR[1]=CTRANS(Z,11.500) ; G54
$P_UIFR[2]=CTRANS(Z,43.710) ; G55
$P_UIFR[3]=CTRANS(Z,22.222) ; G56
$P_UIFR[4]=CTRANS(Z,22.222) ; G57

Thank you, that's exactly what I was after!

I use G10 to load the Fanuc's like that, but I never knew the Siemens way.

I may implement that as well.
Thanks!


-----------------------

Think Snow Eh!
Ox