Drilling question New to the haas mc

bishbash25 · May 13, 2019

Just recently started using the haas control manually to program fanuc programs.

Also uk based.

I have a drilling question regarding G83
After you move say to first position i. e

X10. Y10. It commands to drill at this position say 5mm deep

If the next hole was 10mm deep can i use this line

X20. Y10.,Z-10

Without cancelling with G80 and re writing G83 with Z-10

Thanks

J

Sent from my SM-G950F using Tapatalk

Booze Daily · May 13, 2019

Yes (edit to add characters)

SeymourDumore · May 15, 2019

Yes, you can re-specify ALL G8X parameters on the individual blocks.
X Y Z Q R P G98/G99, even add I J K if you prefer.

In your example though, I hope the comma ( , ) was just a typo. It is not needed and probably will be puked at.

Delw · May 16, 2019

SeymourDumore said:
Yes, you can re-specify ALL G8X parameters on the individual blocks.
X Y Z Q R P G98/G99, even add I J K if you prefer.

In your example though, I hope the comma ( , ) was just a typo. It is not needed and probably will be puked at.

and even add different fixture offsets too

like g00g90x1.0g55
then
g00g90x1.0g56

etc etc

for example

T4M6(120 DEGREE C-SINK)
G90 G00 G56 X-2.326Y-0.468
T5
S3000M3
G43Z0.1H4M8
G82G98Z-.106R+0.1F25.P200
G90 G00 G57 X-2.326Y-0.468
G90 G00 G58 X-2.326Y-0.468
G90 G00 G59 X-2.326Y-0.468
G80M9
G91G28Z0M5
M01

SeymourDumore · May 16, 2019

Delw said:
and even add different fixture offsets too

T4M6(120 DEGREE C-SINK)
G90 G00 G56 X-2.326Y-0.468
T5
S3000M3
G43Z0.1H4M8
G82G98Z-.106R+0.1F25.P200
G90G00G57X-2.326Y-0.468
G90G00G58X-2.326Y-0.468
G90G00G59X-2.326Y-0.468
G80M9
G91G28Z0M5
M01

All is good there Delw, but .... Damm is that an ugly code!!!

How'bout this one:

T4 M06 (120 DEGREE C-SINK)
T5 (PRESTAGE #7 DRILL)
G90
G00 G43 H04 D04
G00 G56 X-2.326Y-0.468 Z1.
S3000 M03
M08
G82 G98 Z-.106 R0.1 F25. P200
G57 X-2.326 Y-0.468
G58 X-2.326 Y-0.468
G59 X-2.326 Y-0.468
G80
M09
M05
G00 G53 Z0
...

Or, even prettier the same thing with drill added:

%
T4 M6 (120 DEGREE SPOT)
T5 (PRESTAGE #7 DRILL)
G90
G00 G43 H04 D04
G00 G56 X-2.326Y-0.468 Z1.
S3000 M03
M08
G82 G98 Z-.106 R0.1 F25. P200 L0
M97 P9000
G80
M09
M05
G00 G49 G53 Z0
T5 M06 (#7 DRILL)
T6 (PRESTAGE 1/4-20 TAP)
G00 G43 H05 D05
G00 G56 X-2.326Y-0.468 Z1.
S1800 M3
M08
G83 G98 Z-1.0 R0.1 F10. P200 Q.25 L0
M97 P9000
G80
M09
M05
G00 G53 Z0
(TAP CODE TO FOLLOW ....)
M30
(START SUBS)
N9000 ( HOLE PATTERN)
G56 X-2.326 Y-0.468
G57 X-2.326 Y-0.468
G58 X-2.326 Y-0.468
G59 X-2.326 Y-0.468
M99
%

SeymourDumore · May 16, 2019

bishbash25 said:
I have a drilling question regarding G83
After you move say to first position i. e

X10. Y10. It commands to drill at this position say 5mm deep

If the next hole was 10mm deep can i use this line

To the OP however:

G00 X10. Y10. Z100.
S3000 M03
M08
G83 G98 Z-5. R2. Q100. P.1 F2.(or whatever)
X20. Y10. Z-10.
X30. Y10. Z-25.
X40. Y10. Z-15.
G80

will be fine...

Matt@RFR · May 16, 2019

I learned something today. Thanks fellas.

thesidetalker · May 16, 2019

Delw said:
and even add different fixture offsets too

like g00g90x1.0g55
then
g00g90x1.0g56

etc etc

for example

T4M6(120 DEGREE C-SINK)
G90 G00 G56 X-2.326Y-0.468
T5
S3000M3
G43Z0.1H4M8
G82G98Z-.106R+0.1F25.P200
G90 G00 G57 X-2.326Y-0.468
G90 G00 G58 X-2.326Y-0.468
G90 G00 G59 X-2.326Y-0.468
G80M9
G91G28Z0M5
M01

Not quite. On Haas control, G00 will cancel a canned cycle.

SeymourDumore · May 16, 2019

thesidetalker said:
Not quite. On Haas control, G00 will cancel a canned cycle.

Ooops! That's correct! Any Group-1 G-code will cancel the canned cycle. Not just on a Haas, but most ( if not all ) controls.
I've actually missed that one before cleaned up his post.

Booze Daily · May 16, 2019

Gonna want to make sure G54, G55, etc. Z surface is within .100 (initial level) of each other or you’ll snap tools going between work offsets. Or make initial level bigger. ie G43 H1 Z1.

Delw · May 16, 2019

thesidetalker said:
Not quite. On Haas control, G00 will cancel a canned cycle.

SeymourDumore said:
Ooops! That's correct! Any Group-1 G-code will cancel the canned cycle. Not just on a Haas, but most ( if not all ) controls.
I've actually missed that one before cleaned up his post.

haha I read your damn that is ugly code went back and read my post. Hell I dont even drink but it was late at night

.
Thanks guys.
I copied and pasted the other lines forgot to edit that out.

sorry about that Glad someone caught it before it was too late.

Booze Daily your 100% correct have to watch the z surface.

Search

Largest Manufacturing Technology Community on the Web

Search

Drilling question New to the haas mc

bishbash25

Plastic

Booze Daily

Titanium

SeymourDumore

Diamond

Delw

Stainless

SeymourDumore

Diamond

SeymourDumore

Diamond

Matt@RFR

Titanium

thesidetalker

Stainless

SeymourDumore

Diamond

Booze Daily

Titanium

Delw

Stainless

Similar threads