OMI-2H and OMP-40-2 Install with P22 1070 skip

Hi,

Just wondering if anyone could shed any light on the correct way to wire in a Renishaw OMI-2H and OMP40-2 to a late 2004 LCD screen VF2SS. I have the probing macros and all required options, found a VQC install manual which describes the wiring for an I/O board without a P77 input, and just using P22 1070 Skip and the M22/M23 spare M relays.

http://www.cam.tuc.gr/DIAFORA JPG/E...n/MANUALS TWN METRHTIKWN/Calibration HAAS.pdf

Also found an OMI SSR to OMI-2H upgrade bulletin using an adapter cable

VS-1/3 - VQCPS - OMI-SSR to OMI-2H Conversion | Haas Automation(R) Resource Center

I'm just a little confused on the correct method to use to get this up and running, and any help would be gladly appreciated, or any photos of control cabinets belonging to machines of similar era with probing installed please?

Ok,

Update is that I have now got power to the OMI-2H and can happily switch between the Table setter or spindle probe using either M52/M53 or M59 P1133/M59 P1134.

I can also run a G31 move and the machine will stop when a probe is triggering the skip input.

Problem comes when I try to calibrate the probes, I am getting a probe open error with the table probe.

Currently I have the probe status outputs from the OMI-2H connected to pins 1 and 2 on the P22 Skip input.

Am I supposed to switch the probe status outputs using a relay and a common?

I'll just keep plugging away here, it may be useful reference for others.

So, skip input was fine, the violet and gray wires from the OMI-2H go to pins 1 & 2 on the P22 skip input.

Relay wiring works like this :-

you run a 24v + to the Common terminal on the M23 relay, and a wire going from the NO contact on M23 to the Common on M22.

White wire ( Machine start input probe1) from OMI-2H goes to NC contact on M22 and Blue (machine start input probe 2) goes to M22 NO

this config will allow correct switching with latest renips_V30.nc probing routine from DIY Haas site.

Spindle probe on
M69 P1134 (Neither Probe on)
M69 P1133 (De-energise M22 relay to select NC Contact)
M59 P1134 (Energise M23 relay to select NO Contact and provide voltage to Probe 1 Machine start input via M22 NC Contact)

Spindle Probe off

M69 P1134 (De-energise M23 no voltage supplied to NC Contact)

OTS On

M69 P1134
M59 P1133 (energise M22 to select NO contact Probe 2 Machine start input)
M59 P1134 (energise M23 to supply 24v to M22 Common)

OTS Off

M69 P1134


I have now successfully run the probe calibration routines step 1 and 2 (Ots XYZ) and spindle probe Z but I am now getting an alarm when i try and run the ring gauge calibration, Illegal Assignment VAR or Value

Here's a video of the auto length and diameter routine running

Renishaw Automatic Tool length and diameter setting on haas vf2ss - YouTube

I can use the spindle probe with the VQCMEB probing macros and the tool probe with the RENIPS_V30 macros but not both at the same time.

I'm considering doing the exact same thing you have done, I'll continue to watch your thread and learn!

Final piece of the puzzle today.

After thinking that the previously mentioned error issue was software based, I obtained an earlier version of the RENIPS macros from Haas version 2.8.

They gave exactly the same error with the spindle probe as the Version 3.0.

As the Spindle Probe routines ran perfectly with VQCPSMEB.NC order macros but the table probe did not, I compared the O09724 settings program which was causing the error.

The issue was that the macro was looking for a parameter 774 which the older control didn't seem to have. other than that the program was identical to the older routine which ran perfectly.

I took a punt and deleted some lines from the program and it runs flawlessly now.


see below lines marked in red which need to be removed.

O09724 (SETTINGS)
G103 P1
G187P2(MEDUIM SETTING)
M98 P9725 (MACHINE CHECK)
M98 P9723
#170= 19 (SELECT DIA OFFSET)
IF [ #6040 EQ 1 ] GOTO90 (RAD DIA)
#170= 3 (SELECT RAD OFFSET)
N90
#161= 556 (START CALIBRATION VARIABLE)
G90 G80 G40 G94
IF [ #4008 NE 49 ] GOTO100
#3000= 89 (NO TOOL LENGTH ACTIVE)
N100
#6996 = 774
#162 = #6998 (STATUS OF PARAMETER 774)
IF [ #4006 EQ 20 ] GOTO400
IF [ #4006 EQ 70 ] GOTO400
#173= 0.05 (INPOS ZONE MM)
#179= 1
#169= 5000 (FAST FEED MM)

IF [ #162 NE 7 ] GOTO140 (SIGMA 5 MOTOR)
IF [ #6507 GT 32000000 ] GOTO150
GOTO145
N140
IF [ #6507 GT 4000000 ] GOTO150
N145
#169= 2500 (FAST FEED FOR SLOW MACHINES- MM)
N150

GOTO500
N400
#173= 0.002 (INPOS ZONE INCH)
#179= 0.04
#169= 200 (FAST FEED INCH)

IF [ #162 NE 7 ] GOTO440 (SIGMA 5 MOTOR)
IF [ #6507 GT 32000000 ] GOTO450
GOTO445
N440
IF [ #6507 GT 4000000 ] GOTO450
N445
#169= 100 (FAST FEED FOR SLOW MACHINES- INCH)
N450

N500
IF [ #[ #161 + 6 ] LE 0 ] GOTO600
IF [ #[ #161 + 6 ] GT 1 ] GOTO600
GOTO700
N600
#[ #161 + 6 ]= 0.2
N700
M99