Help with eia milling in fusion 640t

T

tspiszak

Plastic

Joined

Nov 14, 2016

• Nov 27, 2019

• #1

Hello
Would anyone have a sample program for milling on sqt250 ms in G12.1 mode, face milling, anything simple like external hexagon or square.
For some reason it doesn't work on my lathe. Wrong code? Maybe a parameter needs changing?
See video.

YouTube


Sent from my D5803 using Tapatalk

 

C

chad883

Cast Iron

Joined

Jan 12, 2012

Location

indiana, usa

• Nov 27, 2019

• #2

You need 2 options turned on to do this. 19 Polar coordinate input and 20 cylinderical interpolation, or something like that. Those will allow you to G12.1 and program X and C. If you do not have those options it gets a little more interesting but can be done. To check for options soft key Diag then Version then Options, the darker ones are turned on.

 

T

tspiszak

Plastic

Joined

Nov 14, 2016

• Nov 27, 2019

• #3

I have polar option, don't have cylindrical one. I thought cylindrical was for z and c axis.

Sent from my D5803 using Tapatalk

 

T

tspiszak

Plastic

Joined

Nov 14, 2016

• Nov 27, 2019

• #4

Options

Sent from my D5803 using Tapatalk

 

C

chad883

Cast Iron

Joined

Jan 12, 2012

Location

indiana, usa

• Nov 27, 2019

• #5

T0303 (1/2 BLIZZARD FACE CEM)
G0 G40 G98 M8
M200
G97 S2000 M203

(T-32 MODE)
G10L50(ENABLE PARAMETER WRITE)
N1016R240(CHANGES PARAMETER TO MAKE MACHINE T-32 MODE)
G11(TURN OFF PARAMETER WRITE)

G28 H0
G0 Z0.05 M8
X6.98
C0
G12.1 (POLAR ON)
G1Z0.05 F350.0
G1 X-2.5953Y3.0(X IS NOT DIAMETER DURING THIS)
Z-.5
G41 X-2.3302Y2.7348 F9.0(FEED RATE IS IPM)
G3X-2.065Y2.625I0.2652J0.2652
G1X2.065
G2X2.625Y2.065I0.J-0.56
G1Y-2.065
G2X2.065Y-2.625I-0.56J0.
G1X-2.065
G2X-2.625Y-2.065I0.J0.56
G1Y2.065
G2X-2.065Y2.625I0.56J0.
G3X-1.7998Y2.7348I0.J0.375
G1G40X-1.5347Y3.0
G1 Z0.05 F50.0
G0 Z0.05
X6.73
G40 C0
G13.1(POLAR OFF)
G0 Z0.05

(BACK TO STANDARD MODE)
G10L50
N1016R248

Note that T-32 mode changes the way some of the other cycles function, so I turn it off and on in the program to maintain the normal program for other stuff.
G11

 

C

chad883

Cast Iron

Joined

Jan 12, 2012

Location

indiana, usa

• Nov 27, 2019

• #6

The actual moves are made just like it would be programmed for a mill.

 

T

tspiszak

Plastic

Joined

Nov 14, 2016

• Nov 27, 2019

• #7

I'll try that.
My machine doesn't have y axis. Will it work
?

Sent from my D5803 using Tapatalk

 

C

chad883

Cast Iron

Joined

Jan 12, 2012

Location

indiana, usa

• Nov 27, 2019

• #8

Yes, they Y moves are translated into C moves.

 

T

tspiszak

Plastic

Joined

Nov 14, 2016

• Nov 28, 2019

• #9

Thanks, worked.
Any chance I can do milling in zc axis without cylindrical option
?

Sent from my D5803 using Tapatalk

 

T

tspiszak

Plastic

Joined

Nov 14, 2016

• Dec 2, 2019

• #10

Do you have a working g76 threading cycle you could share. I'm in t32 mode. One line g76.

Sent from my D5803 using Tapatalk

 

C

chad883

Cast Iron

Joined

Jan 12, 2012

Location

indiana, usa

• Dec 2, 2019

• #11

I have never needed to cylindrical mill, so I have not figured out how to do it.

I do not like T-32 mode. That is why I program the parameter change only during the ops I need it, so no I do not have a thread cycle.